Skip to content

Commit

Permalink
BernardCells: tutorial demonstrating Bernard cells
Browse files Browse the repository at this point in the history 
2D buoyancy-driven flow between flat plates with small temperature difference
  • Loading branch information
Chris Greenshields committed Mar 15, 2017
1 parent fbc5595 commit 2598b13
Show file tree
Hide file tree
Showing 17 changed files with 662 additions and 0 deletions.
41 changes: 41 additions & 0 deletions tutorials/heatTransfer/buoyantBoussinesqPimpleFoam/BernardCells/0/T
View file
@@ -0,0 +1,41 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object T;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //

dimensions [0 0 0 1 0 0 0];

internalField uniform 300;

boundaryField
{
floor
{
type fixedValue;
value uniform 301;
}
ceiling
{
type fixedValue;
value uniform 300;
}
sideWalls
{
type zeroGradient;
}

#includeEtc "caseDicts/setConstraintTypes"
}

// ************************************************************************* //
31 changes: 31 additions & 0 deletions tutorials/heatTransfer/buoyantBoussinesqPimpleFoam/BernardCells/0/U
View file
@@ -0,0 +1,31 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volVectorField;
object U;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //

dimensions [0 1 -1 0 0 0 0];

internalField uniform (1e-4 0 0);

boundaryField
{
wall
{
type noSlip;
}

#includeEtc "caseDicts/setConstraintTypes"
}

// ************************************************************************* //
34 changes: 34 additions & 0 deletions tutorials/heatTransfer/buoyantBoussinesqPimpleFoam/BernardCells/0/alphat
View file
@@ -0,0 +1,34 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object alphat;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //

dimensions [0 2 -1 0 0 0 0];

internalField uniform 0;

boundaryField
{
wall
{
type alphatJayatillekeWallFunction;
Prt 0.85;
value $internalField;
}

#includeEtc "caseDicts/setConstraintTypes"
}


// ************************************************************************* //
33 changes: 33 additions & 0 deletions tutorials/heatTransfer/buoyantBoussinesqPimpleFoam/BernardCells/0/epsilon
View file
@@ -0,0 +1,33 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object epsilon;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //

dimensions [0 2 -3 0 0 0 0];

internalField uniform 1e-5;

boundaryField
{
wall
{
type epsilonWallFunction;
value $internalField;
}

#includeEtc "caseDicts/setConstraintTypes"
}


// ************************************************************************* //
33 changes: 33 additions & 0 deletions tutorials/heatTransfer/buoyantBoussinesqPimpleFoam/BernardCells/0/k
View file
@@ -0,0 +1,33 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object k;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //

dimensions [0 2 -2 0 0 0 0];

internalField uniform 1e-5;

boundaryField
{
wall
{
type kqRWallFunction;
value $internalField;
}

#includeEtc "caseDicts/setConstraintTypes"
}


// ************************************************************************* //
33 changes: 33 additions & 0 deletions tutorials/heatTransfer/buoyantBoussinesqPimpleFoam/BernardCells/0/nut
View file
@@ -0,0 +1,33 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object nut;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //

dimensions [0 2 -1 0 0 0 0];

internalField uniform 0;

boundaryField
{
wall
{
type nutkWallFunction;
value $internalField;
}

#includeEtc "caseDicts/setConstraintTypes"
}


// ************************************************************************* //
32 changes: 32 additions & 0 deletions tutorials/heatTransfer/buoyantBoussinesqPimpleFoam/BernardCells/0/p
View file
@@ -0,0 +1,32 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object p;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //

dimensions [0 2 -2 0 0 0 0];

internalField uniform 0;

boundaryField
{
wall
{
type calculated;
value $internalField;
}

#includeEtc "caseDicts/setConstraintTypes"
}

// ************************************************************************* //
33 changes: 33 additions & 0 deletions tutorials/heatTransfer/buoyantBoussinesqPimpleFoam/BernardCells/0/p_rgh
View file
@@ -0,0 +1,33 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
object p_rgh;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //

dimensions [0 2 -2 0 0 0 0];

internalField uniform 0;

boundaryField
{
wall
{
type fixedFluxPressure;
rho rhok;
value $internalField;
}

#includeEtc "caseDicts/setConstraintTypes"
}

// ************************************************************************* //
22 changes: 22 additions & 0 deletions tutorials/heatTransfer/buoyantBoussinesqPimpleFoam/BernardCells/constant/g
View file
@@ -0,0 +1,22 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class uniformDimensionedVectorField;
location "constant";
object g;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //

dimensions [0 1 -2 0 0 0 0];
value (0 -9.81 0);


// ************************************************************************* //
35 changes: 35 additions & 0 deletions tutorials/heatTransfer/buoyantBoussinesqPimpleFoam/BernardCells/constant/transportProperties
View file
@@ -0,0 +1,35 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object transportProperties;
}

// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //

transportModel Newtonian;

// Laminar viscosity
nu [0 2 -1 0 0 0 0] 1e-03;

// Thermal expansion coefficient
beta [0 0 0 -1 0 0 0] 1e-03;

// Reference temperature
TRef [0 0 0 1 0 0 0] 300;

// Laminar Prandtl number
Pr [0 0 0 0 0 0 0] 1.0;

// Turbulent Prandtl number
Prt [0 0 0 0 0 0 0] 1.0;

// ************************************************************************* //
30 changes: 30 additions & 0 deletions ...rials/heatTransfer/buoyantBoussinesqPimpleFoam/BernardCells/constant/turbulenceProperties
View file
@@ -0,0 +1,30 @@
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: dev |
| \\ / A nd | Web: www.OpenFOAM.org |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "constant";
object turbulenceProperties;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //

simulationType laminar;

RAS
{
RASModel kEpsilon;

turbulence on;

printCoeffs on;
}


// ************************************************************************* //

0 comments on commit 2598b13

Please sign in to comment.