Feat/additional example

examples/00-fluent/external_compressible_flow.py

@@ -0,0 +1,360 @@
+""".. _ref_external_compressible_flow_settings_api:
+
+Modeling External Compressible Flow
+-----------------------------------
+The purpose of this tutorial is to compute the turbulent flow past a transonic
+wing at a nonzero angle of attack using the k-w SST turbulence model.
+
+This example uses the guided workflow for watertight geometry meshing
+because it is appropriate for geometries that can have no imperfections,
+such as gaps and leakages.
+
+**Workflow tasks**
+
+The Modeling External Compressible Flow Using the Meshing Workflow guides you through these tasks:
+
+- Creation of capsule mesh using Watertight Geometry workflow.
+- Model compressible flow (using the ideal gas law for density).
+- Set boundary conditions for external aerodynamics.
+- Use the k-w SST turbulence model.
+- Calculate a solution using the pressure-based coupled solver with global time step selected for the pseudo time method.
+- Check the near-wall mesh resolution by plotting the distribution of .
+
+**Problem description**
+
+The problem considers the flow around a wing at an angle of attack a=3.06° and a free stream Mach
+number of 0.8395 (M=0.8395). The flow is transonic, and has a shock near the mid-chord (x/c≃0.20)
+on the upper (suction) side. The wing has a mean aerodynamic chord length of 0.64607 m, a span of 1.1963 m,
+an aspect ratio of 3.8, and a taper ratio of 0.562.
+"""
+
+# sphinx_gallery_thumbnail_path = '_static/external_compressible_flow.png'
+
+###############################################################################
+# .. image:: /_static/external_compressible_flow_011.png
+#   :width: 500pt
+#   :align: center
+
+###############################################################################
+# Example Setup
+# -------------
+# Before you can use the meshing workflow, you must set up the
+# example and initialize this workflow.
+#
+# Perform required imports
+# ~~~~~~~~~~~~~~~~~~~~~~~~
+# Perform required imports, which includes downloading and importing
+# the geometry files.
+
+import ansys.fluent.core as pyfluent
+from ansys.fluent.core import examples
+
+wing_spaceclaim_file, wing_intermediary_file = [
+    examples.download_file(
+        CAD_file, "pyfluent/external_compressible", save_path=pyfluent.EXAMPLES_PATH
+    )
+    for CAD_file in ["wing.scdoc", "wing.pmdb"]
+]
+
+###############################################################################
+# Launch Fluent
+# ~~~~~~~~~~~~~
+# Launch Fluent as a service in meshing mode with double precision running on
+# four processors.
+
+meshing = pyfluent.launch_fluent(
+    precision="double",
+    processor_count=4,
+    mode="meshing",
+    cwd=pyfluent.EXAMPLES_PATH,
+)
+
+###############################################################################
+# Initialize workflow
+# ~~~~~~~~~~~~~~~~~~~
+# Initialize the watertight geometry meshing workflow.
+
+meshing.workflow.InitializeWorkflow(WorkflowType="Watertight Geometry")
+
+###############################################################################
+# Watertight geometry meshing workflow
+# ------------------------------------
+# The fault-tolerant meshing workflow guides you through the several tasks that
+# follow.
+#
+# Import CAD and set length units
+# ~~~~~~~~~~~~~~~~~~~~~~~~~~~~~~~
+# Import the CAD geometry and set the length units to inches.
+
+meshing.workflow.TaskObject["Import Geometry"].Arguments.set_state(
+    {
+        "FileName": wing_intermediary_file,
+    }
+)
+
+meshing.workflow.TaskObject["Import Geometry"].Execute()
+
+###############################################################################
+# Add local sizing
+# ~~~~~~~~~~~~~~~~
+# Add local sizing controls to the faceted geometry.
+
+meshing.workflow.TaskObject["Add Local Sizing"].Arguments.set_state(
+    {
+        "AddChild": "yes",
+        "BOIControlName": "wing-facesize",
+        "BOIFaceLabelList": ["wing_bottom", "wing_top"],
+        "BOISize": 10,
+    }
+)
+
+meshing.workflow.TaskObject["Add Local Sizing"].AddChildAndUpdate()
+
+meshing.workflow.TaskObject["Add Local Sizing"].Arguments.set_state(
+    {
+        "AddChild": "yes",
+        "BOIControlName": "wing-ege-facesize",
+        "BOIFaceLabelList": ["wing_edge"],
+        "BOISize": 2,
+    }
+)
+
+meshing.workflow.TaskObject["Add Local Sizing"].AddChildAndUpdate()
+
+meshing.workflow.TaskObject["Add Local Sizing"].Arguments.set_state(
+    {
+        "AddChild": "yes",
+        "BOIControlName": "boi_1",
+        "BOIExecution": "Body Of Influence",
+        "BOIFaceLabelList": ["wing-boi"],
+        "BOISize": 5,
+    }
+)
+
+meshing.workflow.TaskObject["Add Local Sizing"].AddChildAndUpdate()
+
+###############################################################################
+# Generate surface mesh
+# ~~~~~~~~~~~~~~~~~~~~~
+# Generate the surface mash.
+
+meshing.workflow.TaskObject["Generate the Surface Mesh"].Arguments.set_state(
+    {"CFDSurfaceMeshControls": {"MaxSize": 1000, "MinSize": 2}}
+)
+
+meshing.workflow.TaskObject["Generate the Surface Mesh"].Execute()
+
+###############################################################################
+# Describe geometry
+# ~~~~~~~~~~~~~~~~~
+# Describe geometry and define the fluid region.
+
+meshing.workflow.TaskObject["Describe Geometry"].UpdateChildTasks(
+    SetupTypeChanged=False
+)
+
+meshing.workflow.TaskObject["Describe Geometry"].Arguments.set_state(
+    {"SetupType": "The geometry consists of only fluid regions with no voids"}
+)
+
+meshing.workflow.TaskObject["Describe Geometry"].UpdateChildTasks(SetupTypeChanged=True)
+
+meshing.workflow.TaskObject["Describe Geometry"].Execute()
+
+###############################################################################
+# Update boundaries
+# ~~~~~~~~~~~~~~~~~
+# Update the boundaries.
+
+meshing.workflow.TaskObject["Update Boundaries"].Execute()
+
+###############################################################################
+# Update regions
+# ~~~~~~~~~~~~~~
+# Update the regions.
+
+meshing.workflow.TaskObject["Update Regions"].Execute()
+
+###############################################################################
+# Add boundary layers
+# ~~~~~~~~~~~~~~~~~~~
+# Add boundary layers, which consist of setting properties for the
+# boundary layer mesh.
+
+meshing.workflow.TaskObject["Add Boundary Layers"].Arguments.set_state(
+    {"NumberOfLayers": 12}
+)
+
+meshing.workflow.TaskObject["Add Boundary Layers"].AddChildAndUpdate()
+
+###############################################################################
+# Generate volume mesh
+# ~~~~~~~~~~~~~~~~~~~~
+# Generate the volume mesh, which consists of setting properties for the
+# volume mesh.
+
+meshing.workflow.TaskObject["Generate the Volume Mesh"].Arguments.set_state(
+    {
+        "VolumeFill": "poly-hexcore",
+        "VolumeFillControls": {"HexMaxCellLength": 512},
+        "VolumeMeshPreferences": {
+            "CheckSelfProximity": "yes",
+            "ShowVolumeMeshPreferences": True,
+        },
+    }
+)
+
+meshing.workflow.TaskObject["Generate the Volume Mesh"].Execute()
+
+###############################################################################
+# Check mesh in meshing mode
+# ~~~~~~~~~~~~~~~~~~~~~~~~~~
+# Check the mesh in meshing mode.
+
+meshing.tui.mesh.check_mesh()
+
+###############################################################################
+# Save mesh file
+# ~~~~~~~~~~~~~~
+# Save the mesh file (``wing.msh.h5``).
+
+meshing.tui.file.write_mesh("wing.msh.h5")
+
+###############################################################################
+# Solve and postprocess
+# ---------------------
+# Once you have completed the watertight geometry meshing workflow, you can
+# solve and postprcess the results.
+#
+# Switch to solution mode
+# ~~~~~~~~~~~~~~~~~~~~~~~
+# Switch to solution mode. Now that a high-quality mesh has been generated
+# using Fluent in meshing mode, you can switch to solver mode to complete the
+# setup of the simulation.
+
+solver = meshing.switch_to_solver()
+
+###############################################################################
+# Check mesh in solver mode
+# ~~~~~~~~~~~~~~~~~~~~~~~~~
+# Check the mesh in solver mode. The mesh check lists the minimum and maximum
+# x, y, and z values from the mesh in the default SI units of meters. It also
+# reports a number of other mesh features that are checked. Any errors in the
+# mesh are reported.
+
+solver.mesh.check()
+
+###############################################################################
+# Define model
+# ~~~~~~~~~~~~
+# Set the k-w sst turbulence model.
+
+# model : k-omega
+# k-omega model : sst
+
+solver.setup.models.viscous.model = "k-omega"
+
+solver.setup.models.viscous.k_omega_model = "sst"
+
+###############################################################################
+# Define materials
+# ~~~~~~~~~~~~~~~~
+# Modify the default material ``air`` to account for compressibility and variations of the thermophysical properties with temperature.
+
+# density : ideal-gas
+# viscosity : sutherland
+# viscosity method : three-coefficient-method
+# reference viscosity : 1.716e-05 [kg/(m s)]
+# reference temperature : 273.11 [K]
+# effective temperature : 110.56 [K]
+
+air = solver.setup.materials.fluid["air"]
+
+air.density.option = "ideal-gas"
+
+air.viscosity.option = "sutherland"
+
+air.viscosity.sutherland.option = "three-coefficient-method"
+
+air.viscosity.sutherland.reference_viscosity = 1.716e-05
+
+air.viscosity.sutherland.reference_temperature = 273.11
+
+air.viscosity.sutherland.effective_temperature = 110.56
+
+###############################################################################
+# Boundary Conditions
+# ~~~~~~~~~~~~~~~~~~~
+# Set the boundary conditions for ``pressure_farfield``.
+
+# gauge pressure : 0 [Pa]
+# mach number : 0.8395
+# temperature : 255.56 [K]
+# x-component of flow direction : 0.998574
+# z-component of flow direction : 0.053382
+# turbulent intensity : 5 [%]
+# turbulent viscosity ratio : 10
+
+pressure_farfield = solver.setup.boundary_conditions.pressure_far_field[
+    "pressure_farfield"
+]
+
+pressure_farfield.gauge_pressure = 0
+
+pressure_farfield.m = 0.8395
+
+pressure_farfield.t = 255.56
+
+pressure_farfield.flow_direction[0] = 0.998574
+
+pressure_farfield.flow_direction[2] = 0.053382
+
+pressure_farfield.turb_intensity = 0.05
+
+pressure_farfield.turb_viscosity_ratio = 10
+
+###############################################################################
+# Operating Conditions
+# ~~~~~~~~~~~~~~~~~~~~
+# Set the operating conditions.
+
+# operating pressure : 80600 [Pa]
+
+solver.setup.general.operating_conditions.operating_pressure = 80600
+
+###############################################################################
+# Initialize flow field
+# ~~~~~~~~~~~~~~~~~~~~~
+# Initialize the flow field using hybrid initialization.
+
+solver.solution.initialization.hybrid_initialize()
+
+###############################################################################
+# Save case file
+# ~~~~~~~~~~~~~~
+# Solve the case file (``external_compressible1.cas.h5``).
+
+solver.file.write(file_name="external_compressible.cas.h5", file_type="case")
+
+###############################################################################
+# Solve for 25 iterations
+# ~~~~~~~~~~~~~~~~~~~~~~~~
+# Solve for 25 iterations (100 iterations is recommended, however for this example 25 is sufficient).
+
+solver.solution.run_calculation.iterate(iter_count=25)
+
+###############################################################################
+# Write final case file and data
+# ~~~~~~~~~~~~~~~~~~~~~~~~~~~~~~~
+# Write the final case file and the data.
+
+solver.file.write(file_name="external_compressible1.cas.h5", file_type="case")
+
+###############################################################################
+# Close Fluent
+# ~~~~~~~~~~~~
+# Close Fluent.
+
+solver.exit()
+
+###############################################################################